Fanuc Series 15i/150i-MA (Programming) Operators Manual

B-63324EN/03 PROGRAMMING 10.TOOL FUNCTION (T FUNCTION)
- 251 -
Example
- Tool change method A
A tool group command (T code) specified in a block containing the tool
change command (M06) functions as a command for returning the tool
to the magazine. By specifying a tool group number with a T code, the
number of the tool being used is output using a T code signal. If a
specified tool number differs from the tool group of the tool being used,
an alarm (PS0442) is issued. By setting bit 6 (ABT) of parameter No.
7400 to 1, however, the alarm can be suppressed.
Example: Assume that the tool life management ignore number is 100.
T101 ; Selects a group 1 tool whose service life has not expired.
: (Assume that tool number 010 is selected.)
M06 ; Counts the service life of a tool of group 1.
: (The service life counting for tool number 010 starts.)
T102 ; Selects a group 2 tool whose service life has not expired.
: (Assume that tool number 100 is selected.)
M06 T101 ; Counts the service life of a tool of group 2.
: (The service life counting for tool number 100 starts.)
: The number of the tool being used (tool of group 1) is output using a
: T code signal. (Tool number 010 is output.)
T103 ; Selects a group 3 tool whose life has not expired.
: (Assume that tool number 200 is selected.)
M06 T102 ; Counts the service life of a tool of group 3.
: (The service life counting for tool number 200 starts.)
G43 H99 ; Uses tool length compensation for the tool selected from group 3.
:
G41 D99 ; Uses cutter compensation for the tool selected from group 3.
:
D00 ; Cancels cutter compensation.
:
H00 ; Cancels tool length compensation

Leave a Reply

Your email address will not be published. Required fields are marked *