Fanuc Series 15i/150i-MA (Programming) Operators Manual

13.FUNCTIONS TO SIMPLIFY PROGRAMMING PROGRAMMING B-63324EN/03
- 318 -
13.1.14 Example of Canned Cycle
Offset value +200.0 is set in offset No.11, +190.0 is set in offset No.15, and +150.0 is set in offset No.31
N001G92X0Y0Z0; Coordinate setting at reference position
N002G90G00Z250.0T11M6; Tool change
N003G43Z0H11; Initial level, tool length offset
N004S30M3; Spindle start
N005G99G81X400.0Y-350.0Z-153.0R-97.0F120; Positioning, then #1 drilling
N006Y-550.0; Positioning, then #2 drilling and point R level return
N007G98Y-750.0; Positioning, then #3 drilling and initial level return
N008G99X1200.0; Positioning, then #4 drilling and point R level return
N009Y-550.0; Positioning, then #5 drilling and point R level return
N010G98Y-350.0; Positioning, then #6 drilling and initial level return
N011G00X0Y0M5; Reference position return, spindle stop
N012G49Z250.0T15M6; Tool length offset cancel, tool change
N013G43Z0H15; Initial level, tool length offset
N014S20M3; Spindle start
N015G99G82X550.0Y-450.0 Z-130.0R-97.0P300F70; Positioning, then #7 drilling, point R level return
N016G98Y-650.0; Positioning, then #8 drilling, initial level return
N017G99X1050.0; Positioning, then #9 drilling, point R level return
N018G98Y-450.0; Positioning, then #10 drilling, initial level return
N019G00X0Y0M5; Reference position return, spindle stop
N020G49Z250.0T31M6; Tool length offset cancel, tool change
N021G43Z0H31; Initial level, tool length offset
N022S10M3; Spindle start
N023G85G99X800.0Y-350.0 Z-153.0R47.0F50; Positioning, then #11 drilling, point R level return
N024G91Y-200.0L2; Positioning, then #12, 13 drilling. point R level return
N025G28X0Y0M5; Reference position return, spindle stop
N026G49Z0; Tool length offset cancel
N027M0; Program stop

Leave a Reply

Your email address will not be published. Required fields are marked *